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Creating a surfaces that is from 2 distant surfaces

Question asked by Rick Campbell on Oct 3, 2007
Latest reply on Oct 4, 2007 by Rick Campbell

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Hello,

I have a bottle that I am creating. I would like to createone surface between two separate parts of the bottle (meshtogether). It is not possible to use a loft due to the factof the complex shape. I would also like it to follow 4 guidecurves if possible.
I have attached the part to look at. The feature I am tryingto do I put the sketches in the following folder: SurfaceMesh Attempt

You will be able to get a better idea of what I am talking aboutafter looking at the sketches in this folder

1-9C36HC Oct 4, 2007 12:40 PM

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here is the 2007 version

See the reply in context

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Matt Lombard Oct 3, 2007 7:39 PM
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I don't see an attached file.
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- Rick Campbell @ Matt Lombard on Oct 3, 2007 7:45 PM
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  It won't let me add any files. Is there a specific file Ishould be trying to attach?
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  - Charles Culp @ Rick Campbell on Oct 3, 2007 7:53 PM
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    Rick, to attach files to posts on this forum, you first have to.zip the file. You can attach only image files (.png, .gif,.jpg) and .zip files.
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    - Rick Campbell @ Charles Culp on Oct 3, 2007 8:00 PM
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      OK, Thank You. This is just one idea I am trying
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      - Charles Culp @ Rick Campbell on Oct 3, 2007 8:38 PM
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        are you talking about surface-loft2? If so, I would create itas 2 lofts on the side, and then a surface fill on the roundedsides. First do the flat edges as lofts, then do the roundedprofiles. Just make sure to set your end constraints to betangent where required. I have attached a sample.
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        070034-01_CC.zip395.9 KB
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        Rick Campbell @ Charles Culp on Oct 4, 2007 11:21 AM
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        This one is close. Thank you! I will try to play withit. I attached a jpeg of what the right side view is supposeto look like. The Shoulder area is not quite there yet
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      - Matt Lombard @ Rick Campbell on Oct 3, 2007 9:37 PM
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        I've got one attached too. You've got to look at things differently when using surfaces. Think of modeling the part face by face. From there you have to determine how the faces should be broken up, and that has to be done by thinking of features. The way you were doing it was not quite duplicating the round faces on the sides, so I removed the arc from the guide curves, and just lofted along the straight line. Plus, the whole thing is simplified by using symmetry. Beyond that there are a couple of special tools to know.
        
        I'm not sure exactly what kind of look you were going for, but the attached part is one take on it. There are many different approaches you could take. This is just one of them.
        
        Best of luck
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        matt.zip843.6 KB
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        Rick Campbell @ Matt Lombard on Oct 4, 2007 11:34 AM
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        Would you happen to save you file in 2007 SP4.0 so I could take alook at it. Thank You
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        1-9C36HC @ Rick Campbell on Oct 4, 2007 12:40 PM
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        here is the 2007 version
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        Rick Campbell @ 1-9C36HC on Oct 4, 2007 12:44 PM
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        Wow Mark!! That is nice! I am going to have take sometime and study how you did that so nice.
        
        I want to thank everybody that helped me. You were all great! It really helped!! Now my boss won't get all crazy.
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        Rick Campbell @ 1-9C36HC on Oct 4, 2007 1:17 PM
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        Hi Mark,
        
        I have feeling this is going to a very simple question. Inthe Surface-Fill1 feature, how did you pick Edge<1> Tangent -S1- Boundary without picking a whole profile.
        
        I don't know how to just pick the edge, I am getting profiles orsketches.
        
        Thanks again for the help.
        
        Rick
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        Charles Culp @ Rick Campbell on Oct 4, 2007 1:24 PM
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        If you want to get an edge instead of a sketch, the easiest optionis to right click on the sketch and "Hide" it. Another option is to right click on the sketch in the viewingarea, and "select other". A list will come up ofobjects that are underneath the cursor.
        
        If you still get an entire sketch, instead of just one segment, youhave a different problem. Then you right click and choose"Selection Manager". I suggest reading thesolidworks help file on how that works. Basically it givesyou options of either selecting just one line segment, a loop, or acontinuous segment.
        
        Good luck!
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        1-9C36HC @ Rick Campbell on Oct 4, 2007 2:04 PM
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        Rick,
        
        The solution is to use the Fill surface because your design calls for filling an area that is not a regular 4 sided case, but rather 5 sided. The Fill I created for your design is a combination of C0 (contact) and C1 (tangent) boundaries, based on your intent.
        
        The trick to making fill work well is to assign tangency to as many boundaries that your design intent allows for; by doing this, the tangent boundaries of the fill better control the "flow" and "fairness" of the fill surface.
        
        You'll notice that what I did in your part is created 3 extruded surfaces to control the fill. If you rollback to the fill surface and show all the surface bodies in your surface folder, I think this will answer your question.
        
        Of course, the way I introduced this solution to your current part is a hack, and you should rebuild your part to add or eliminate extraneous features.
        
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        Rick Campbell @ 1-9C36HC on Oct 4, 2007 7:14 PM
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        I learned a lot from you design. Thank You!
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1-9C36HC Oct 3, 2007 9:28 PM
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Rick,

Is this what your looking for?
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- Rick Campbell @ 1-9C36HC on Oct 4, 2007 11:23 AM
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  It looks like the part is in a future version. I have 2007;SP4.0. I am going to contact the IT guy to get me the latestService Pack. Thank You, I will let you know if it works assoon as I can open it.
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Designer Designer Oct 4, 2007 12:28 PM
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Hi Rick ...

You must open Matt`s & MB`s file using solidworks 2008.

Regards,
DD
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Creating a surfaces that is from 2 distant surfaces

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