I think the one I see most often (and one which I haven't directly addressed in my FAQ discussion), is when someone has made changes to a drawing template and wants to update old drawings to the new standard.
I guess I should be specific about also wishing to see your answer to your FAQ.
hear by my selection
- Why does my balloon number not match my Bom?
Link the view to the bom ( right click on the view / properties link to bom)
- Why are my tangent edges not following the phantom option as set in the document properties?
make sure your view is set to tangent edges with font and not tangent edges visible
- When I change my font in the document properties . my note won't change?
Make sure your notes have the option use document font on
- why is my flatpattern folded on the drawing?
( people often open the part by right clicking the flatpattern view and choose open. Solidworks will go to the model in the flatpattern configuration.
People then click flatten to see the model in it's folded state. when going back to the drawing , the flatpattern view is in folded state.
Solutions is to always make sure that the 3d model is flattend in the flatpattern configuration)
- why is my drawing view empty / why are my drawings views empty when saving to dxf.
( Solidworks can't convert the view from draft to high quality because a part in the 3d assembly has a corrupt boudingbox / display state.
How do i find this Problem?
1) go to your model and set the model to hlr and high quaility
2) supress every component and start unsupressing from the top. When your model disappears after an unsuppress you know that is your guilty part.
3 open that part. put it in HLR and High quality and rebuild. Issue should be fixed
Q: Why is the view bounding box way bigger than the model, and how do I shrink it?
A: There might be a sketch or other hidden geometry that extends out past the model. To shrink it draw a box that is the size you want and create a cropped view.
Q: How do I create a broken view at an angle other than horizontal or vertical?
A1: You can't.
A2: Create the break by doing a cut extrude in the model itself.
A3: Make 2 copies of the view and add a break to each of them. Set the gap size to something larger than the paper width so that only half of the view is on the sheet, then line up both halves by eye.
That's a good one, I haven't seen that before. Thanks!
Why is this drawing extremely slow to update.?
We work with car bodies with very many complex surface and this slows down especially section views. Furthermore views contains different car parts.
There are many possible answers but most common is "Use display states extensively and don't use configurations just to hide some items".