I want the bottom of the part to match the front plane as shown ........ How can this be done?
Make the bottom of the part normal to the screen and then hit the spacebar. There's a button on there to change the views, select it and then hit the front view icon.
I think the view orientation purpose this will work. But if you need to align the face with the front plane you may have to Move/Copy body.
Steve's answer will work if you're setting up the views.
If you need to reorient the part itself, you can use the Move / Copy Bodies feature and align the body using planes
Right click "Sketch1" and select "Edit Sketch Plane". Then select "Front plane". I cant help to notice that Sketch1 is not fully defined so it might change geometry during this exercise.
Another, more involved method.
Create a new coordinate system aligned the way you want it.
New Coordinate system
Save As a step file. Click on options.
Click on Output Coordinate System, select the coordinate system you just created.
Open the step file you just created.
Run Import Diagnostics
Run Feature recognition
Your model should now be aligned the way you want it.
Hope this helps.
Hey Tony have you used move copy bodies tool in the direct editing toolbar? You can execute the same re-orientation in about half the time without loosing your feature tree.
Yes I have. I actually use it all the time. You're absolutely right. It does take about half the time.
I was just offering an alternative method.
I've found it useful at times.
Sounds good, sorry if my original comment came off condescending, coffee hasn't quite kicked in yet.
No Problem. I wasn't offended at all.
Michael Hoft See if this helps...
Global Coordinate System Orientation - Which Way is Up?
My first thought is to just edit the feature so it is how you want it...rather than having it modeled wrong and then adding more features such as Move Body to locate it correctly. In short, model it right to begin with instead of being sloppy.
I do Move/Copy Body very frequently upon imported models from vendors. I conform linear axial orientation along X Axis, where for example a ball valve model may be provided to me with the direction of pipe connections along the Y Axis. Some control panel enclosure models are provided from vendor with its back down on the Top Plane, which would make sense when they are manufacturing it, but is never the orientation in which I need to apply their product. Even worse, I've found some imported models to have all their Bodies arbitrarily very far from the Origin, perhaps as an isolated portion of a 'master part' which potentially contained many product models. Any of these cases can benefit from relation based re-positioning, to conform similar parts within the Library so they can be interchanged with minimal redefinition.
Original Poster's issue clearly resides in a self-generated part, or at least a very simple start of a part in which the Sketch can be edited more properly as you suggest. I'm only saying that this is not always the case.
Retrieving data ...