As a work around, if you went up to the 'top' of the through hole and straight across to the vertical in the slot it might work.
James, I tried the way you described and didn't like how it came out - it did work though. Thank for the help!
Try this: edit cutting line.
1. Edit cutting line.
2. Edit sketch
3. Make angled line construction.
Aaron, When you initially create the section view you need to select the "legacy foreshortened section view" option. Selecting to create a "standard section view" will generate the result you have where the section appears longer than expected.
If the option no longer shows up you should be able to find the message here ...
Aaron, your request is an extremely rare case. It technically is not supported by ASME or ISO standards. However, SOLIDWORKS does support it, with limitations. Since this is a non-standard type of section view, Section View Assist does not support this. You'll have to make your sketch from scratch (as I suspect you already have).
- Create sketch, associated with the geometry you wish to cut.
- Select any line segment of your sketch.
- Start the Section View command.
- You will automatically have a preview of the section view attached to your cursor. Do not place your section view yet.
- In the Section View PropertyManager, add a check to "Foreshorten view". This is a legacy option that is only available at the time of view creation. You will not be able to change this setting what you place your view (to remove or add a check).
- Place your view.
This limitation of this option is that it produces legacy section view (pre-SW2013). So, it's behavior is less advanced than current section views (with inherent issues and otherwise reduced functionality associated with the old system). However, when we updated section view behavior in SW2013, we made this an option for just your exact scenario, as rare as it may be. The SW2013+ section views support far more scenarios, with more reliable results. This is the one known scenario we could not support with the new system.